Why don’t the residuals converge in my conjugate heat transfer problem in Fluent and is there any way I can converge the solution?
January 25, 2023 at 7:16 amFAQParticipant
Occasionally it may be difficult to converge the energy equation in Fluent for a conjugate heat transfer problem. The most common causes of the problem and their resolutions are summarized here. Causes: ========= 1. Poor mesh quality: high size change, and/or high skewness, and/or coarse mesh 2. High jump in thermal conductivity 3. Invalid boundary conditions 4. Improper mesh scaling Resolutions: ========= 1. Make sure mesh is scaled properly. Go to Mesh –> Scale 2. Double-check model setup and boundary conditions 3. Reduce explict-relaxation, using the following 3 lines: (rpsetvar ‘temperature/explicit-relax? #f) (rpsetvar ‘explicit-relaxation? #t) (rpsetvar ‘temperature/explicit-relax 0.1) By default, explicit-relax is set to 1.0. 4. Keep implicit underrelaxation to 1.0, by using the following line: (rpsetvar ‘temperature/relax 1) 5. Use alternative wall formulation, which can be activated using the following TUI command: /solve set expert , yes , , , 6. Ignore secondary gradients on all the cells, but shell conduction walls (if you have them), by using the following rpvar: (rpsetvar ‘temperature/secondary-gradient? #f) By default, this is #t (true). To obtain the value, type: rpgetvar ‘temperature/secondary-gradient?) which will return either #t or #f. Warning: This may bring some measureable inaccuracy, depending on how skewed the cells are at the wall and how high is the magnitude of the wall heat flux. 7. If you have turned on shell conduction in any of the walls, ignore secondary gradient in shell conduction zones only using the following command: (rpsetvar ‘temperature/shell-secondary-gradient? #f) This does not cause measurable inaccuracy.
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- How can I create a Cell Register from a Cell Zone?
- Left-handed faces troubleshooting
- How to overcome the model information incompatible with incoming mesh error?
- Delete or Deactivate Zone in Fluent
- ANSYS Fluent: Introduction to the GEKO Turbulence Model Part I
- How to create and execute a FLUENT journal file?
- ANSYS System Coupling: Two Way Fluid Structure Interaction – Part 1
- Running Python Script from Workbench
- What are the requirements for an axisymmetric analysis?
- How can I Export and import boxes / Systems from one Workbench Project to another?