Why doesn’t my Harmonic analysis with a viscoelastic material show any phase lag with a prestressed static structural analysis?


January 25, 2023 at 7:34 amFAQParticipant
This behavior is a limitation with the linear perturbation method. Viscoelasticity can be modeled either in the time or frequency domain. In the time domain, we have a (real) stiffness that changes as a function of applied stress and time. In the frequency domain (harmonic), we have complex stiffness (storage and loss moduli) that is a function of frequency. Now, when we use linear perturbation, we start off in the time domain (static is a special case where time doesn’t change). We construct a tangent stiffness matrix based on the deformed shape and stress from the ‘base state’, but this constructed tangent stiffness matrix is a real matrix. There is no provision to develop a complex stiffness (i.e., imaginary stiffness matrix) from timedomain results. If you have no linear perturbation (regular harmonic), we construct complex stiffness from viscoelastic data (based on undeformed shape). However, once you use linear perturbation, you are limited to using a real stiffness matrix only. That is why you lose the phase lag – namely, you no longer have the imaginary stiffness term present. A way around this is to use damping instead of harmonic viscoelasticity. This can be achieved with TB,ELASTIC and TB,SDAMP. The drawbacks are that (a) you don’t get viscoelastic behavior in your base static/transient analysis and (b) since we use damping [C] instead of imaginary stiffness [K’], stress and strain will be inphase. However, by substituting the imaginary [K’] with [C], you get the phase lag based on input excitation compared with output response.

Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center HighMounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center highmounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized KOmega) turbulence model offers a flexible, robust, generalpurpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
 ANSYS ACCS: Simulation of a Composite Rib Using ANSYS Composite Cure Simulation Tool
 Hyperelastic Simulations
 Why the anisotropic stiffness matrix in Engineering Data highlighted in yellow?
 How to investigate fracture mechanics parameters for a thin geometry?
 When the material data sheet of a polymer reports both the Tensile and the Flexural Modulus, which value may be used in place of Young’s Modulus?
 Does it make sense to use viscoelastic material in static structural since it requires the calculation of strain rate?
 What is the slope of the multilinear hardening plasticity curve beyond the last user defined stress/strain value?
 How does the analysis interpret the time beyond the shear relaxation test data? Will it be a linear behavior. Say, I have shear relaxation data for 10 minutes, and I set my analysis to run for a time of 20 minutes.
 What is the slope of the multilinear hardening plasticity curve beyond the last user defined stress/strain value?
 How does the analysis interpret the time beyond the shear relaxation test data? Will it be a linear behavior. Say, I have shear relaxation data for 10 minutes, and I set my analysis to run for a time of 20 minutes.
© 2023 Copyright ANSYS, Inc. All rights reserved.