Why doesn’t my Harmonic analysis with a visco-elastic material show any phase lag with a pre-stressed static structural analysis?
January 25, 2023 at 7:34 amFAQParticipant
This behavior is a limitation with the linear perturbation method. Viscoelasticity can be modeled either in the time or frequency domain. In the time domain, we have a (real) stiffness that changes as a function of applied stress and time. In the frequency domain (harmonic), we have complex stiffness (storage and loss moduli) that is a function of frequency. Now, when we use linear perturbation, we start off in the time domain (static is a special case where time doesn’t change). We construct a tangent stiffness matrix based on the deformed shape and stress from the ‘base state’, but this constructed tangent stiffness matrix is a real matrix. There is no provision to develop a complex stiffness (i.e., imaginary stiffness matrix) from time-domain results. If you have no linear perturbation (regular harmonic), we construct complex stiffness from viscoelastic data (based on undeformed shape). However, once you use linear perturbation, you are limited to using a real stiffness matrix only. That is why you lose the phase lag – namely, you no longer have the imaginary stiffness term present. A way around this is to use damping instead of harmonic viscoelasticity. This can be achieved with TB,ELASTIC and TB,SDAMP. The drawbacks are that (a) you don’t get viscoelastic behavior in your base static/transient analysis and (b) since we use damping [C] instead of imaginary stiffness [K’], stress and strain will be in-phase. However, by substituting the imaginary [K’] with [C], you get the phase lag based on input excitation compared with output response.
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- Question: What is the difference between PLNSOL, EPPL, EQV and PLNSOL,NL,EPEQ?
- ANSYS ACCS: Simulation of a Composite Rib Using ANSYS Composite Cure Simulation Tool
- ANSYS Mechanical: Delamination Analysis using Contact Debonding
- Is Johnson Cook model supported for static structural analysis?
- Hyperelastic Simulations
- How to use layered section to simulate composites and post process the results in ANSYS Mechanical
- Guidelines of modeling a gasket.
- Does it make sense to use viscoelastic material in static structural since it requires the calculation of strain rate?
- What are Isochronous stress-strain curves? How can they be used in ANSYS for modeling creep?
- When the material data sheet of a polymer reports both the Tensile and the Flexural Modulus, which value may be used in place of Young’s Modulus?