March 17, 2023 at 8:59 amFAQParticipant
1. Start with converged steady-state solution when applicable (when the initial transient solution is not important). 2. You could use either SIMPLEC (will be fastest if holds together) or coupled solver. Alternatively, depending on the simulation, you could start with SIMPLEC and then switch to the coupled solver. 3. All Under Relaxation Factors are to be kept at 1 ( or close to 1 provided stability is achieved). 4. Courant = infinity (1e+06) in pressure based coupled solver (which is no relaxation). 5. dt is chosen such as to maintain convective CFL =1 (this value can be reported under velocity) and acoustic CFL =1 (if solving for acoustics). 6. No more than 10 iterations / time step. More than that are not needed if CFL ~1. 7. You could “ignore” the residuals as long as they drop per time step. Dropping of residuals to 3 orders of magnitude is not absolutely necessary, especially continuity. 8. In transient solution, residuals do not represent converged solution. Flow variables are not converged during sub iterations, what is updated during sub iterative cycle is flux values which come from the previous step and then are updated using the flow variables at the current step. However, to monitor convergence, you could use the variable of interest and monitor the variation as the simulation progresses.
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- How can I create a Cell Register from a Cell Zone?
- Left-handed faces troubleshooting
- How to overcome the model information incompatible with incoming mesh error?
- Delete or Deactivate Zone in Fluent
- ANSYS Fluent: Introduction to the GEKO Turbulence Model Part I
- How to create and execute a FLUENT journal file?
- ANSYS System Coupling: Two Way Fluid Structure Interaction – Part 1
- Running Python Script from Workbench
- What are the requirements for an axisymmetric analysis?
- How can I Export and import boxes / Systems from one Workbench Project to another?