March 1, 2022 at 10:18 pmFAQParticipant
Problems with a CHT analysis in CFX can manifest themselves as unphysically high temperatures in a solid due to poor mesh quality of that solid. If very high temperatures are generated, use CFD-Post to isolate the location of concern then check the mesh quality in this area. If the minimum orthogonality angle is less than 10 degrees in this area, try to remesh it to improve the quality. It has also been shown that resolving the temperature gradient near the interface with inflation layers will help. Unphysically high temperatures near the fluid solid interface can also be caused by the use of 1:1 interfaces. A conformal mesh can be used for CHT cases, however if unphysically high temperatures are encountered, GGI interfaces should be used. If convergence problems and/or unphysical temperature peaks persist the recommendation is to change the diffusion scheme used with the CHT model. To do this, you need to use the expert parameter ‘”cht diffusion scheme”. A more robust but less accurate scheme (positive definite values) is used if the parameter is set to:
EXPERT PARAMETERS: cht diffusion scheme = 3 END
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- Simulating Battery Pack Cooling System Using Ansys Fluent
- Thermal Analysis of a Radiator Using Ansys Fluent
- ANSYS Fluent Student: Conjugate Heat Transfer in a Heat Sink
- Defining heat transfer coefficient (HTC)
- ANSYS Fluent: Overview of the Mapped Interface Technique for CHT Simulations (18.2)
- What are the TUI commands to enable / disable Shell Conduction?
- How much number of faces per cluster value should be used for S2S radiation model in ANSYS Fluent?
- How do I determine if I must consider natural or forced convection?
- How to read solar load data files from serial ANSYS Fluent versions before 18.2 in a newer serial version?
- Plate Heat Exchanger Solver Setup in ANSYS Student – Part 1
© 2023 Copyright ANSYS, Inc. All rights reserved.