QUESTION: I get the error shown below when I use the ANISO material model. My tensile yield in the x, y, and z directions is 102,000 psi and my compressive yield in all 3 directions is 72,000 psi. Satisfaction of the consistency equation only appears to allow for very small differences between tensile and compressive yield strength. For instance, a difference of 15 psi would satisfy it, but that small difference would be useless to me, and to most others for that matter. ***************************** *** ERROR *** CP= 2.125 TIME= 18:02:13 TheTB,ANISO table for material 1 has anisotropic yield stresses that do not satisfy the consistency equation requirement. Consistency equation equals 1.058823529E05 which must be less that 1.883239171E09. Improve the accuracy of the input yield stresses. ***************************** Are there any other material models that can handle real differences between the tensile and compressive response for materials with a history of cold rolling?


March 17, 2023 at 9:00 amFAQParticipant
Unless one is willing to accept the different value of yield stress in one of the directions, the consistent condition will never be met. If both the elastic and plastic responses of the material are completely isotropic, and the only is difference is yield stress in tension and compression, then use the cast iron option to mimic the behavior by using TB,CAST,1 tbdata,1,0.5 TB,uniaxil,1,,,TENSION tbpt,,,, TB,uniaxil,1,,,COMPRESSION tbpt,,,, ADDITIONAL DETAILS: The option of using tb,cast option was suggested as the properties of this material are very close to isotropic in both elasticity and plasticity. The only special thing here is that they have difference yield stress and tension and compression. It is actually not really an orthotropic material, which is why it was suggested to use the cast option with plastic Poissonâ€™s to 0.5. This will ignore the Rankin yield surface assumption in cast iron and is a purely VonMises yield surface in tension and compression. The cast iron option allows different tension and compression behavior, and it is what we want here. So if a user has an isotropic material but with different yields in tension and compression, they should use TB,CAST with Poisson=0.5.

Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center HighMounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center highmounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized KOmega) turbulence model offers a flexible, robust, generalpurpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1Â provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
 ANSYS ACCS: Simulation of a Composite Rib Using ANSYS Composite Cure Simulation Tool
 Hyperelastic Simulations
 Why the anisotropic stiffness matrix in Engineering Data highlighted in yellow?
 Does it make sense to use viscoelastic material in static structural since it requires the calculation of strain rate?
 When the material data sheet of a polymer reports both the Tensile and the Flexural Modulus, which value may be used in place of Young’s Modulus?
 How to investigate fracture mechanics parameters for a thin geometry?
 What is the slope of the multilinear hardening plasticity curve beyond the last user defined stress/strain value?
 How does the analysis interpret the time beyond the shear relaxation test data? Will it be a linear behavior. Say, I have shear relaxation data for 10 minutes, and I set my analysis to run for a time of 20 minutes.
 What is the slope of the multilinear hardening plasticity curve beyond the last user defined stress/strain value?
 How does the analysis interpret the time beyond the shear relaxation test data? Will it be a linear behavior. Say, I have shear relaxation data for 10 minutes, and I set my analysis to run for a time of 20 minutes.
Â© 2023 Copyright ANSYS, Inc. All rights reserved.