How to resolve the warning “materials in neighbor cell threads (6 and 7) of interior zone 1 are of different types” with a mesh coming from Ansys Meshing?
January 25, 2023 at 7:16 amFAQParticipant
When loading a mesh from Ansys Meshing into Fluent it can occur that the following warning message is printed many times: Warning: materials in neighbor cell threads (6 and 7) of interior zone 1 are of different types (aluminum and air). This problem MUST be fixed before solving The reason for this can be a conflicting definition of material type (fluid, solid) in Ansys Meshing For example the issue will become visible with the following settings: 1. no material assignment in geometry 2. body name includes the text “fluid” 3. Named Selection (NS) is defined on the same body, but without the text “fluid” 4. Default setting of “Auto Zone Type Assignment = On” is set in Ansys Meshing (AM) In this scenario the material type is undefined by the geometry. So it gets automatically defined in AM. As the body name includes “fluid” the body will be defined as fluid type. However, as the NS does not include “fluid” the material type gets overridden as solid. Due to this overriding no “Interior Wall” is defined between the fluid and neighbor solid bodies. This results in the warnings in Fluent. The solution is one of the following: 1. define the material type in geometry and deactivate “Auto Zone Type Assignment” 2. define the material type in AM on the body and deactivate “Auto Zone Type Assignment” 3. use “fluid” in the body name and do not define Named Selections on the body (i.e. only on faces of the body but not on the volume) 4. do not change the default body names and use “fluid” in the Named Selection on the body Or check the following: If the “Auto Zone Type Assignment” is active (default) and a body is defined as fluid (by type or name) than a specified NS on the body must also have the text “fluid” in its name. The “Auto Zone Type Assignment” can be set in the options of Ansys Meshing in File > Options > Meshing > Export > Ansys Fluent > Auto Zone Type Assignment
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- How can I create a Cell Register from a Cell Zone?
- Left-handed faces troubleshooting
- How to overcome the model information incompatible with incoming mesh error?
- ANSYS Fluent: Introduction to the GEKO Turbulence Model Part I
- Delete or Deactivate Zone in Fluent
- How to create and execute a FLUENT journal file?
- ANSYS System Coupling: Two Way Fluid Structure Interaction – Part 1
- Running Python Script from Workbench
- What are the requirements for an axisymmetric analysis?
- How can I Export and import boxes / Systems from one Workbench Project to another?