January 25, 2023 at 7:16 amFAQParticipant
Often, Chemical Engineers need to compute the RTD of their Continuous stirred tank reactors (CSTRs). FLUENT’s DPM model is challenging to use in these systems due to difficulty in getting statistically meaningful number of particles at the outlet. A second method is to introduce passive tracer material either with species or user-defined scalars. A method with user-defined scalars (UDS) is outlined here. Approach: 1. Solve for single-phase steady state flow field with inlets and outlets. 2. Switch to unsteady solver. 3. Introduce a UDS with mass flux as convection term and default unsteady term. The UDS represents a passive tracer that is used to determine RTD. 4. Change UDS diffusivity to zero or reasonable values. For water-water system, this is quite low ~ 1e-10 m2/s. 5. For pulse input, patch a known amount of UDS near the inlet; for step input, make UDS value = 1 at inlet. 6. Turn on surface monitor of area-av. UDS value at the outlet. Plot, print/ write to file. 7. Turn off all equations except the UDS equation. Run for the required flow time. The UDS conc. at the outlet as a function of time can be used to extract the residence time distribution. If you use step input of tracer (UDS value = 1 at inlet), the outlet UDS profile when normalized (Coutlet/Cinlet) is called F curve which is a cumulative residence time distribution. If you introduce a pulse, the normalized response is called C Curve which is the RTD function.
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- ANSYS Fluent: Introduction to the GEKO Turbulence Model Part I
- ANSYS Polyflow: Adaptive Meshing Based on Contact
- Delete or Deactivate Zone in Fluent
- What is meant by Warning: Flow boundary zone 18 is adjacent to a solid zone?
- Apply Custom Material Properties in Fluent
- Aero-Mechanical Simulation of Turbomachinery Blading
- ANSYS System Coupling: Two Way Fluid Structure Interaction – Part 1
- Check CPU Time in ANSYS FLUENT
- Predict Gearbox Lubrication, Oil Temperature and Churning Losses using CFD Simulation
- Running Python Script from Workbench