Tagged: ls-dyna, LS-DYNA Suite, lsdyna, structural-mechanics
March 17, 2023 at 8:59 amFAQParticipant
Tied contacts in LS-DYNA can have either a constraint-based or a penalty-based formulation. The penalty-based formulation is invoked by including the OFFSET option in the contact keyword name. Exception is the CONSTRAINED_OFFSET type, which is still constraint-based. While a node (of a deformable or of a rigid body) can be constrained by multiple penalty-based tied contacts at the same time, a node of a deformable body can be a node of just a single constraint-based tied contact definition. If the same node is found in more than one constraint-based tied contacts, LS-DYNA will constrain that node only with the constrained-based tied contact that appears first in the input file. The remaining tied contacts will not be considered for that node and appropriate warning messages will be written in the message and d3hsp files (namely, Warning 40552 in SMP and Warning 30455 in MPP). The IPBACK flag (3rd field, Optional Card E of *CONTACT) is only applicable to constraint-based tied contacts. By activating IPBACK, an identical penalty-based contact is generated with the OFFSET type (or in the case of the SHELL_EDGE constrained-base contact, a BEAM_OFFSET type is generated). The ID of the generated interface will be set to the ID of the original interface plus 1 if that ID is available, or it will be otherwise set the maximum used contact ID plus 1. For nodes successfully tied by the constraint-based contact there will an extra redundant penalty tying, but for nodes dropped from the constraint contact due to other conflicting constraints (including those of rigid bodies) the tying will be handled solely by the automatically generated penalty-based tied contact. In MPP, nodes successfully tied with the constraint-based contact will be skipped by the penalty-based contact.
Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center High-Mounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center high-mounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized K-Omega) turbulence model offers a flexible, robust, general-purpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1 provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
- The warning message is: “The maximum contact stiffness is too big. This may affect the accuracy of the results.” Why does large contact stiffness affect results accuracy?
- Contact Definitions in ANSYS Workbench Mechanical
- After Workbench crashes, how can I recover the project from a .mechdb file?
- Model has a large number of contacts – how to reduce them?
- How to resolve “Error: Invalid Geometry”?
- How to display the color of each body based on the material in Mechanical?
- Please explain the warning message “coefficient ratio exceeds 10e8” ?
- How to locate an element of a particular ID number in Mechanical?
- How to Connect Excel to Workbench
- How can I plot bodies colored by material property in Workbench?
© 2023 Copyright ANSYS, Inc. All rights reserved.